Machine Tokens

Machine Tokens

What Is a Machine Token? 

A machine token is a software feature in Microvellum Toolbox that allows users to add 3D representations of various machining operations to parts of a product. This includes aspects like cutouts, camlocks, dados, routes, and more. There are 3 categories of machine tokens in Microvellum: Associative tokens, Non-Associative tokens, and Drawing Only tokens. The functionality of each type is explained in the section below. Attached to this article is a PDF listing all tokens and parameters in this article for easy viewing. 

Types of Machine Tokens

Associative Tokens

Associative machine tokens are used to perform routing, sawing, or drilling operations on the part that contains the machine token and a part that touches or is penetrated by the part. For example, a dado machine token is associative. The dado is applied to an edge face, and the associative machining for the dado is applied to the part that is being penetrated. In the case of a construction hole token (dowel and/or screw), the token is applied to an edge face, and the associative machining is applied to the part that is being touched.

Non-Associative Tokens

Non-Associative machine tokens are used to perform routing, sawing, or drilling operations on a single face or corner of a part. Non-Associative machine tokens include machine operations like corner notches, chamfers, boring, grooves, and polylines.  

Drawing Only Tokens

Drawing Only machine tokens are used to add 3D representations of machining that will not appear in G-code, being added to parts for exclusively visual purposes. 

All Machine Tokens 


Machine tokens are applied to parts through the Part Properties interface in Toolbox. To add a new machine token, open the product and part you wish to add the token to in Part Properties, select the "Machining Tokens" tab of the "Parts" interface (the bottom tab on the left side of the center console), right-click in the center, and click "Add".   

All machine tokens as of the latest iteration of the Microvellum Foundation Library are listed below, categorized according to which type of machine token they are, with example formats of how the values are meant to be entered in the Part Properties interface. 

Associative Tokens

All associative tokens are listed below. With the vast majority of Associative Tokens, the token is normally placed in a part with a name and a number representing the numbered edge or face of the token is being applied to. For instance, a token named “CAMLOCK5” can be read as follows: ‘CAMLOCK’ is the name and type of token, while '5' is the edge or face number. 

CAMLOCK


Camlock tokens drill a series of holes in the edge specified by the first argument and place a series of holes in a panel that touches the specified face. They also drill a hole for the cam lock in the face of the panel. This token is listed as "Associative Cam Locks" within the Part Properties interface. 

Parameter 1 – Hole Locations – Format: 2, 11.5, 21.125
Enter the dimension from the edge of the panel to the hole. If you want more than one hole, enter a distance for the location of each hole, separated by commas. 
Parameter 2 – Edge Bore Diameter (Metric) – Format: 8
Use the second parameter to enter the edge bore diameter. 
Parameter 3 – Edge Bore Depth – Format: 0.875
Use the third parameter to enter the edge bore depth. 
Parameter 4 – Z Location
Use the fourth parameter to enter the dimension in the Z-axis to drill the horizontal hole. If left blank, the hole will be centered on the panel edge.
Parameter 5 – Face Bore Diameter 1 2 (Metric) – Format: 8, 15
Use the fifth parameter to enter the face bore diameter of the holes for the shaft, followed by a comma and then the face bore diameter of the cam lock. 
Parameter 6 – Face Bore Depth 1 2 – Format: 0.5, 0.5
Use the sixth parameter to enter the face bore depth of the holes for the shaft, followed by a comma and then the face bore depth of the cam lock. 
Parameter 7 – Backset – Format: 1|3.25
Use the seventh parameter to enter the dimension from the edge of the part to the center of the cam adjuster. You can add multiple holes by using a pipe symbol to delimit each separate value. 
Parameter 8 – CamFace – Format: 5
Use the eighth parameter to enter the face on which to drill the cam lock hole. Specify 5 or 6. 
Parameter 9 – Drill from the Opposite Side – Format: 1|-2|.875
Use the ninth parameter for three cam lock token options. Separate each option with a pipe symbol.
  1. Use the first option for opposite face drilling. Enter a value of 1 if you would like to drill the construction holes on the opposite face from the intersecting parts - commonly known as a face 6 machining operation. This is used primarily for countersinking but not limited to any other face drilling operation.  
  2. Use the second option to offset the opposite face drilling center from the edge drilling center. A positive value and negative value can be used to adjust the face hole position.
  3. Use the third value to offset the entire array. Each value in parameter 1 will be moved along the panel edge by an amount equal to the value entered in this option.

DADO

 
The Dado token places a groove in a panel that penetrates the specified face by a specified amount, using a router tool. This token is listed as "Associative Dado with Router" within the Part Properties interface. 

Parameter 1 – Lead-In | Stop Dado Gap – Format: 1.25|0.25
This parameter controls the length of the route at the starting end.
  1. Enter a positive dimension to force the router to increase the route length. 
  2. Enter a negative dimension to force the router to decrease the route length.
  3. Leave blank and the route will be the length of the panel. 
Use a pipe symbol followed by a gap amount to automatically clip the ends of the panel for a Stop Dado. The total nip amount will be the lead-in value plus the gap amount.
Parameter 2 – Options – Format: 0|1|0|0
Currently, there are four usable options that can be used with each needing to be separated by the pipe symbol (|).
  1. The first option is used to reverse the direction of the route. 
    1. A value of 0 runs the route normally. 
    2. A value of 1 will change route direction, but only if it is a single-pass route. 
    3. A semi-colon followed by a 1 in this parameter will flip the male lead in and out amounts if they do not line up. 
  2. The second option is used to flip the route or adjust where the gap of the route is placed. 
    1. With a value of 0, no changes are made.
    2. With a value of 1, the route is flipped moving the gap to the other side. 
      1. If you have a lock dado or mortise and tenon joint, a value of 1 will flip the lock dado or flip the dimensions of the mortise and tenon. 
    3. With a value of 2, the gap is centered between the two sides. 
  3. The third option will allow you to override the global setting for Ramp Associative Dados. 
    1. With a value of 0, this dado will not ramp. 
    2. With a value of 1, the dado will ramp. 
  4. The fourth option with a value of 1 will create a lead-in on a single line route that doesn’t have one and cannot be added from the other parameters. This parameter is not set by default. 
Parameter 3 – Beginning Depth – Format: 0.25
Enter the depth of the dado in this parameter.
Parameter 4 – Lead-Out | Stop Dado Gap – Format: -1.25|0.25
This parameter controls the length of the route at the finishing end.
  1. Enter a positive dimension to force the router to increase the route length. 
  2. Enter a negative dimension to force the router to decrease the route length.
  3. Leave blank and the route will be the length of the panel. 
Use a pipe symbol followed by a gap amount to automatically clip the ends of the panel for a Stop Dado. The total nip amount will be the lead-in value plus the gap amount.
Parameter 5 – Dado Thickness – Format: 0.375
Enter the thickness of the dado here. The tool being used automatically determines how the dado is routed.
Parameter 6 – Lock Joint Depths – Format: 0.382|0.425
If you want to make a lock joint, enter the depth of the route that makes the tongue. If you want a tenon joint, enter the depth of the route for the first face followed by a pipe or comma and then enter the depth of route for the second face.
Parameter 7 – Dado Tool | Clip Tool – Format: 102
Enter the tool number for the dado on the associated part. Use a pipe symbol followed by the tool number for the clip on the main part. If none is listed, the first tool will be used for both operations.
Parameter 8 – Panel Penetration – Format: -0.25
The amount the part penetrates the associated panel. Must be a negative number.
Parameter 9 – Tongue Tool Number – Format: 101,102
The tool number for the tongue. For a mortise and tenon joint enter two tool numbers separated by a pipe or comma.

SAW

 
Saw tokens place a groove in a panel that penetrates the specified face by a specified amount, using a sawing tool. This token is listed as "Associative Dado with Saw" within the Part Properties interface. 

Parameter 1 – Lead-In | Stop Dado Gap – Format: 1.25|0.25
This parameter controls the length of the route at the starting end.
  1. Enter a positive dimension to force the router to increase the route length. 
  2. Enter a negative dimension to force the router to decrease the route length.
  3. Leave blank and the route will be the length of the panel. 
Use a pipe symbol followed by a gap amount to automatically clip the ends of the panel for a Stop Dado. The total nip amount will be the lead-in value plus the gap amount.
Parameter 2 – Options – Format: 0|1|0|0
Currently, there are four usable options that can be used with each needing to be separated by the pipe symbol (|).
  1. The first option is used to reverse the direction of the route. 
    1. A value of 0 runs the route normally. 
    2. A value of 1 will change route direction, but only if it is a single-pass route. 
      1. A semi-colon followed by a 1 in this parameter will flip the male lead in and out amounts if they do not line up. 
  2. The second option is used to flip the route or adjust where the gap of the route is placed. 
    1. With a value of 0, no changes are made.
    2. With a value of 1, the route is flipped moving the gap to the other side. 
      1. If you have a lock dado or mortise and tenon joint, a value of 1 will flip the lock dado or flip the dimensions of the mortise and tenon.  
    3. With a value of 2, the gap is centered between the two sides. 
  3. The third option will allow you to override the global setting for Ramp Associative Dados. 
    1. With a value of 0, this dado will not ramp. 
    2. With a value of 1, the dado will ramp. 
  4. The fourth option with a value of 1 will create a lead-in on a single line route that doesn’t have one and cannot be added from the other parameters. This parameter is not set by default. 
Parameter 3 – Beginning Depth – Format: 0.25
Enter the depth of the dado in this parameter.
Parameter 4 – Lead-Out | Stop Dado Gap – Format: -1.25|0.25
This parameter controls the length of the route at the finishing end.
  1. Enter a positive dimension to force the router to increase the route length. 
  2. Enter a negative dimension to force the router to decrease the route length.
  3. Leave blank and the route will be the length of the panel. 
Use a pipe symbol followed by a gap amount to automatically clip the ends of the panel for a Stop Dado. The total nip amount will be the lead-in value plus the gap amount.
Parameter 5 – Dado Thickness – Format: 0.375
Enter the thickness of the dado here. The tool being used automatically determines how the dado is routed.
Parameter 6 – Lock Joint Depths – Format: 0.382|0.425
If you want to make a lock joint, enter the depth of the route that makes the tongue. If you want a tenon joint, enter the depth of the route for the first face followed by a pipe or comma and then enter the depth of route for the second face.
Parameter 7 – Dado Tool | Clip Tool – Format: 102
Enter the tool number for the dado on the associated part. Use a pipe symbol followed by the tool number for the clip on the main part. If none is listed, the first tool will be used for both operations.
Parameter 8 – Panel Penetration – Format: -0.25
The amount the part penetrates the associated panel. Must be a negative number.
Parameter 9 – Tongue Tool Number – Format: 101,102
The tool number for the tongue. For a mortise and tenon joint enter two tool numbers separated by a pipe or comma.

SLIDE

 
Slide tokens place a series of holes for drawer slide mounting in a panel that is away from the specified face by a specified dimension. This token is listed as "Associative Machining for Drawer Slides" within the Part Properties interface. 

Parameter 1 – Dim from Drawer Bottom – Format: 1.818
The dimension from the bottom of the drawer to the center of the hole.
Parameter 2 – Dimension to First Hole – Format: 1.49606
The dimension from the edge of the panel to the first hole.
Parameter 3 – Dimension to Second Hole – Format: 1.49606
The dimension from the edge of the panel to the second hole.
Parameter 4 – Dimension to Third Hole – Format: 1.49606
The dimension from the edge of the panel to the third hole.
Parameter 5 – Dimension to Fourth Hole – Format: 1.49606
The dimension from the edge of the panel to the fourth hole.
Parameter 6 – Dimension to Fifth Hole – Format: 1.49606
The dimension from the edge of the panel to the fifth hole.
Parameter 7 – Face Bore Depth | Diameter – Format: 0.5118|5
The depth to drill the drawer slide holes. If you want to override the global variable for the hole diameter, enter the diameter following a pipe symbol.
Parameter 8 – Drawer Slide Clearance – Format: 0.28528
This column is used to specify the gap between the drawer side and the part to receive the machining.

HWR

HWR tokens place an array of associative hardware on a panel. Machining is controlled by the hardware’s machining tokens in the material file. This token is listed as "Associative Hardware Array" within the Part Properties interface. 

Parameter 1 – Hardware Name
Enter the name of the hardware. 
Parameter 2 –  X Value – Format: 1,25
Enter the distance to the insert point of the hardware in X. Separate values with a comma if entering multiple values. 
Parameter 3 – Y Value – Format: 1,25
Enter the distance to the insert point of the hardware in Y. Separate values with a comma if entering multiple values.
Parameter 4 – X End – Format: 24,456
The dimension in X if you want an array of hardware. Leave blank for only one piece of hardware.
Parameter 5 – Y End – Format: 24,456
The dimension in Y if you want an array of hardware. Leave blank for only one piece of hardware.
Parameter 6 – Distance Between Hardware – Format: 10,225
Enter the distance between the hardware for multiple hardware or leave blank if you want only one piece of hardware.
Parameter 7 – Rotation – Format: 180
Enter the rotation of the hardware about the Z-axis of the part it is associated with. The rotation should be expressed in degrees. 

HINGE

 
Hinge tokens place two holes for each mounting plate in a panel named by the second argument. They can also (optionally) drill holes necessary for hinge mounting on the back of the door. This token is listed as "Associative Machining for Hinges" within the Part Properties interface. 

Parameter 1 – Distance to Bottom Hinge
The dimension from the bottom of the door to the center of the hinge.
Parameter 2 – Distance to Hinge Top
The dimension from the center of the first hinge to the center of the second hinge.
Parameter 3 – Max Hinge Spacing
The maximum distance between hinges.
Parameter 4 – Use 32mm
Leave blank for equal spacing. Enter any value if you want the hinge spacing on 32mm increments.
Parameter 5 – X Offset
Enter the distance from the side of the door to the cabinet side. (Door reveal)
Parameter 6 – Y Offset
Enter the distance from the back of the door to the edge of the cabinet. (Door gap)
Parameter 7 – Face Bore Depth| Diameter
The depth of the hole. If you want to override the global variable for the hole diameter, enter the diameter following a pipe symbol.
Parameter 8 – Mounting Plate Backset
The distance from the edge of the panel to the center on the mounting plate holes.
Parameter 9 – Tool Number
Enter the tool number used for pocket routing if you want to route your hinge cups. Leave blank if you want to use a drill instead.

CONST

 
Const tokens drill a series of holes in the edge of a panel specified in the first argument, as well as placing a series of holes in the panel that touch the specified face. This token is listed as "Associative Const Holes (Type 1)" within the Part Properties interface. 

Parameter 1 – Dimension to First Const Hole – Format: 38.5
The dimension from the edge of the panel to the first construction hole.
Parameter 2 – Dimension to Last Const Hole – Format: 13.5
The dimension from the edge of the panel to the last construction hole.
Parameter 3 – Edge Bore Depth – Format: 0.875
The edge bore depth of the first and second holes.
Parameter 4 – Edge Bore Diameter – Format: 8
The edge bore diameter of the first and second holes.
Parameter 5 – Face Bore Depth – Format: 0.625
The face bore diameter of the first and second holes.
Parameter 6 – Face Bore Diameter – Format: 38.5
The face bore diameter of the first and second holes.
Parameter 7 – Drill from Opposite Side – Format: 0
Parameter used for opposite face drilling. Enter 1 if you would like to drill the construction holes on the opposite face of the intersecting parts. Commonly known as a face 6 machining operation. Used primarily for countersinking but not limited to any other face drilling operation.
Parameter 8 – Second Hole at 32mm – Format: 1
Entering ‘1' will cause the program to provide an additional set of holes 32mm back from the first and last construction hole. Enter '0' if you do not want the additional holes.
Parameter 9 – Distance Between Holes – Format: 127
Enter the distance between holes or leave blank to use the distance between holes specified in the global file.

HOLES

 
Holes tokens drill a series of holes in the edge of a panel at exact specified locations, as well as place a series of holes in the panel that touch the specified face. This token is listed as "Associative Const Holes (Type 2)" within the Part Properties interface. 

Parameter 1 – Hole Locations – Format: 1.125, 10.5, 28.75
The dimension from the edge of the panel to the hole. If you want more than one hole, enter each location separated by commas.
Parameter 2 – Edge Bore Diameter – Format: 8
The edge bore diameter.
Parameter 3 – Edge Bore Depth – Format: 5
The edge bore depth. 
Parameter 4 – Offset Front Edge – Format: 0.175
The offset from the front edge. This parameter must be turned on under the Machining tab in options.
Parameter 5 – Face Bore Diameter – Format: 8
The face bore diameter.
Parameter 6 – Face Bore Depth – Format: 0.472
The face bore depth.
Parameter 7 – Drill from the Opposite Side – Format: 1
Parameter used for opposite face drilling. Enter 1 if you would like to drill the construction holes on the opposite face of the intersecting parts. Commonly known as a face 6 machining operation. Used primarily for countersinking but not limited to any other face drilling operation.
Parameter 8 – Z Value – Format: 0.25
The dimension in Z to drill the horizontal hole. If left blank the 'Construction Holes Z Value' variable will be used from the Global file.  If that global variable is left blank the hole will be centered on the panel.

MODEEZ

 
Modeez tokens drill two holes and a route in the edge specified by the first argument and places a hole in a panel that touches the specified face. This token is listed as "Associative Modeez Fastener" within the Part Properties interface. 

Parameter 1 – Hole Locations – Format: 1.125, 10.5, 28.75
The dimension from the edge of the panel to the hole. If you want more than one hole, enter each location separated by commas.
Parameter 2 – Edge Bore Diameter – Format: 8
The edge bore diameter. 
Parameter 3 – Edge Bore Depth – Format: 5
The edge bore depth.
Parameter 5 – Face Bore Diameter – Format: 8
The face bore diameter. 
Parameter 6 – Face Bore Depth – Format: 0.472
The face bore depth. 
Parameter 7 – Tool Number – Format: 104
Enter the tool number. 
Parameter 8 – Direction – Format: 1
This parameter controls the direction of the fastener. Enter either 1 or 2 to control the direction.

POCKETMORTISE

 
A Pocket Mortise token drills a series of holes in the edge specified by the first argument and places a series of holes in a panel that touches the specified face. It also routes a series of ramped routes in the face of the panel for the pocket screw. This token is listed as "Associative Pocket Mortise" within the Part Properties interface. 

Parameter 1 – Hole Locations – Format: 2.125, 8.5, 21.75
The dimension from the edge of the panel to the hole. If you want more than one hole, enter each location separated by commas.
Parameter 2 – Edge Bore Diameter – Format: 8
The edge bore diameter.
Parameter 3 – Edge Bore Depth – Format: 5
The edge bore depth. 
Parameter 4 – Mortise Face – Format: 6
Face for Pocket. Must be 5 or 6.
Parameter 5 – Face Bore Diameter – Format: 5
The face bore diameter.
Parameter 6 – Face Bore Depth – Format: 0.525
The face bore depth.
Parameter 7 – Tool Number – Format: 104
The tool number.
Parameter 8 – Vector Number – Format: 1
Enter 1 if you want the pocket to contain only one ramp, otherwise the pocket will contain two ramped vectors.
Parameter 9 – Sequence Number – Format: 0
Enter a number that represents the sequence priority of the route. 1 is the highest priority and 0 (the default) is the lowest priority meaning the sequence will be determined automatically. Use sequence numbers over 1000 to force them to come after all other routes.

SHLF

 
Shlf tokens place a series of shelf holes in a panel that is away from a specified face by a specified dimension. This token is listed as "Associative Adjustable Shelf Holes (Type 1)" within the Part Properties interface. 

Parameter 1 – Space From Bottom – Format: 9.75, 247.7
The space from the bottom of the associated panel to the bottom shelf hole. 
Parameter 2 – Dim to First Row – Format: 2.476, 60
The dimension from the edge of the shelf to the first row of shelf holes.
Parameter 3 – Face Bore Depth – Format: 0.275
This parameter controls the hole depth. 
Parameter 4 – Space From Top – Format: 5.75, 146
The space from the top of the associated panel to the top shelf hole.
Parameter 5 – Dim to Second Row – Format: 19.44, 490.8
The dimension from the edge of the shelf to the second row of shelf holes.
Parameter 6 – Face Bore Diameter – Format: 6
This parameter controls the hole diameter. 
Parameter 7 – Shelf Hole Spacing – Format: 1.26, 32
This parameter controls the distance between shelf holes. If left blank the global variable "Shelf Hole Spacing" will be used. To override the global variable "Shelf Hole Spacing," enter the distance between holes here.
Parameter 8 – Shelf Clip Gap – Format: 0.0625, 1.5875
The gap between the edge of the shelf and the face of the associated panel.
Parameter 9 – Reverse Direction – Format: 1
Enter a value if you want the shelf holes to start at the top of the panel and go down. Leave blank if you want the shelf holes to start at the bottom of the panel and go up.

SHELF

 
A Shelf token places a series of shelf holes in a panel that is away from the specified face by a specified dimension. The shelf holes added will run a specified distance from the shelf and not along the entire panel. The associated part machine point will determine space from top and bottom of shelf. This token is listed as "Associative Adjustable Shelf Holes (Type 2) " within the Part Properties interface. 

Parameter 1 – Space From Bottom – Format: 2.2, 56
The space from the bottom of the shelf to the bottom shelf hole.  The bottom of the shelf is determined by the parts machine point.
Parameter 2 – Dim to First Row – Format: 1.85, 381
The dimension from the edge of the shelf to the first row of shelf holes.
Parameter 3 – Face Bore Depth – Format: 0.4375
This parameter controls the depth of the hole. 
Parameter 4 – Space From Top – Format: 2.8
The space from the bottom of the shelf to the top shelf hole.  The bottom of the shelf is determined by the parts machine point.
Parameter 5 – Dim to Second Row – Format: 17.9
The dimension from the edge of the shelf to the second row of shelf holes.
Parameter 6 – Face Bore Diameter – Format: 4
This parameter controls the diameter of the hole. 
Parameter 7 – Shelf Hole Spacing – Format: 1.29|18|32
This parameter controls the distance between shelf holes and the distance between shelf hole rows. If left blank, the global variable "Shelf Hole Spacing & Shelf Row Spacing" will be used. 
  1. To override the global variable "Shelf Hole Spacing," enter the distance between holes here. 
  2. To override the global variable "Shelf Row Spacing," enter a pipe symbol (|) followed by the distance between rows.
Parameter 8 – Shelf Clip Gap – Format: 0.03, 0.75
The gap between the edge of the shelf and the face of the associated panel.
Parameter 9 –Reverse Direction – Format: 1
A value of 1 will flip the space from the top and the space from the bottom parameters.

SHELFSTD

 
A Shelfstd token places a route in a panel that is away from the specified face by a specified dimension. This token is listed as "Associative Adjustable Shelf Standard" within the Part Properties interface. 

Parameter 1 – Space From Bottom – Format: 2.2, 56
The space from the bottom of the associated panel to the bottom of the route.
Parameter 2 – Dim to First Row – Format: 1.85, 381
The dimension from the edge of the panel to the first route.
Parameter 3 – Face Bore Depth – Format: 0.4375
The route depth.
Parameter 4 – Space From Top – Format: 1.526
The space from the top of the associated panel to the top of the route.
Parameter 5 – Dim to Second Row – Format: 1.80|235
The dimension from the edge of the panel to the second route.  The second value is the distance between shelf row routes, separated with a pipe symbol (|). If there is no value the global Shelf Row Spacing will be used.
Parameter 6 – Route Width – Format: 0.197
The width of the route. If you want to make only one pass with the tool, leave this cell blank.
Parameter 7 – Shelf Std Tool Number – Format: 103
The tool number. 
Parameter 8 – Shelf Clip Gap – Format: 0.08, 0.65
The gap between the edge of the shelf and the face of the associated panel.
Parameter 9 –Reverse Direction – Format: 1
Enter a 0 or leave this value blank to force the router to go from the largest Y value to the smallest Y value. Enter a 1 to reverse the direction.

SHELFSTANDARD

 
A Shelf Standard token places a route in a panel that is away from the specified face by a specified dimension. This token is listed as "Associative Adjustable Shelf Standard per shelf " within the Part Properties interface. 

Parameter 1 – Space From Bottom – Format: 9.75
The space from the bottom of the associated panel to the bottom of the route.
Parameter 2 – Dim to First Row – Format: 2.375
The dimension from the edge of the panel to the first route.
Parameter 3 – Face Bore Depth – Format: 5.75
The route depth.
Parameter 4 – Space From Top – Format: 5.75
The space from the top of the associated panel to the top of the route.
Parameter 5 – Dim to Second Row – Format: 19.44|3.275 
The dimension from the edge of the panel to the second route.  The second value is the distance between shelf row routes, separated with a pipe symbol (|). If there is no value the global Shelf Row Spacing will be used.
Parameter 6 – Route Width Format: 0.175
The width of the route. If you want to make only one pass with the tool, leave this cell blank.
Parameter 7 – Shelf Std Tool Number Format: 105
The tool number. 
Parameter 8 – Shelf Clip Gap – Format: 0.0625
The gap between the edge of the shelf and the face of the associated panel.
Parameter 9 –Reverse Direction – Format: 1
Enter a 0 or leave this value blank to force the router to go from the largest Y value to the smallest Y value. Enter a 1 to reverse the direction.

ASSOCPLINE

 
The ASSOCPLINE token was created to facilitate the use of parametric polylines where two parts touch. The token can be used to guide machining along a specific route on the part's surface, using nine parameters for precise control. This token is listed as "Associative Polyline" within the Part Properties interface. 

Parameter 1: Vector Locations – Format: 0.375;0.025|0.375;6;0.25
Enter the X, Y, and Z coordinates of each vector of the routing sequence. Each point should be separated by a semi-colon. Each group of points should be separated by a pipe.
Parameter 2: Bulge List – Format: 1.75;2.221;7.675
Enter the bulge for each vector, 0 for a straight-line route. Separate each value with a semi-colon. If the entry is left blank, all vectors will be straight.
Parameter 3: Feed Speeds – Format: 1.1;0.725;2.82
If you want to control the feed speed of the machine on a per vector basis, make a semi-colon separated list with the feed speed of each vector listed. If the entry is left blank, the feed speed in the material file will be used. If no feed speed is found in the material file, the feed speed in the tool file will be used.
Parameter 4: Options – Format: 1;0;1;0;1;0;1.5
This parameter provides seven options. Separate each value with a semi-colon. If the entry is left blank, all default option settings will be used. 
  1. With the first option, enter a 1 if the token is for machine code only. Enter a 2 if the token is for drawing purposes only. Enter a 0 (the default) if the token is used for both. 
  2. For the second option, enter a 1 if you want the polyline to be drawn as a region or enter a 0 (the default) if you don't (Valid for closed polylines only). 
  3. For the third option, enter a 1 if you want the first vector to be treated as a lead-in, meaning that it will be ignored for drawing purposes. Otherwise, enter 0 (the default). 
  4. For the fourth option, enter a 1 if you want the last vector to be treated as a lead-out, meaning that it will be ignored for drawing purposes. Otherwise, enter 0 (the default). 
  5. For the fifth option, enter a number that represents the sequence priority of the route. 1 is the highest priority and 99 is the lowest priority. With a value of 0, the sequence will be determined automatically. 
  6. For the sixth option enter a value that will be passed to the tool file to control the route angle. 
  7. For the seventh option enter a value that will be passed to the tool file for the angle depth for the route. A tool file must be configured to support options 6 and 7.
Parameter 5: Offset|Rotation – Format: 21.1;2.8;9.81|1.21;0.857;6.25
This parameter can contain two groups of points that should be separated by a pipe. For the first group of points, enter an X, Y, and/or Z offset from the values in parameter 1. Each point should be separated by a semi-colon. For the second group of points enter the X center, Y center, and rotation angle. Each point should be separated by a semi-colon. All the points in parameter 1 will first be offset and then rotated about the center point by the rotation angle specified.
Parameter 6: Profile File Name – Format: Profile5.dwg
If you want to assign a profile cutter to the token, enter the drawing name here.
Parameter 7: Tool Number – Format: 103
The tool number.
Parameter 8: Tool Offset – Format: 1.91
The offset of the router bit.
Parameter 9: Penetration Value – Format: 0
The amount the part penetrates the associated panel. Positive values will penetrate the associated part; negative values will be away from the associated part.

PLINEFROMHOLES

 
The PLINEFROMHOLES token allows you to specify hole locations on an edge and create a polyline route on an associated parts face.  This token is listed as "Associative Polyline from Drilling" within the Part Properties interface. 

Parameter 1 – Hole Locations – Format: 1.4567, 37.780, 0.209, 8.189
The dimension from the edge of the panel to the hole. If you want more than one hole, enter each location separated by commas.
Parameter 2 – Route at Hole – Format: 1|0|1
For each hole location enter in a 1 to turn on the associated polyline route for that hole. If no route is needed for a hole location enter in a 0. Each value should be separated by a pipe symbol (|).
Parameter 3 – Edge Bore – Format: 5|0.387|0.5|9.5
This parameter provides 5 options. Each option’s value must be separated with a pipe symbol (|).  
  1. The first option is the diameter of the edge drilling.  
  2. The second option is the depth of the edge drilling. 
  3. The third option is the distance to offset the drilling from the center of the edge. This is an optional value. 
  4. The fourth option will allow you to enter a distance value that will add a hole for each original hole location in Parameter 1. The route will not be applied to the associated part for this extra hole.  
  5. The fifth option will allow you to enter the desired hole offset insertion point for certain invisible Fastener machine connections.
Parameter 4 – Vector Locations – Format: 1;1|1;10;0.25|250;250;6.5
Enter the X, Y, and Z coordinates of each vector of the routing sequence. Each point should be separated by a semi-colon. Each group of points should be separated by a pipe.
Parameter 5 – Bulge List – Format: 0;1;1;0
Enter the bulge for each vector, 0 for a straight line route. Separate each value with a semi-colon. If the entry is left blank, all vectors will be straight.
Parameter 6 – Feed Speeds – Format: 1;2;2;1
If you want to control the feed speed of the machine on a per vector basis, make a semi-colon separated list with the feed speed of each vector listed. If the entry is left blank, the feed speed in the material file will be used. If no feed speed is found in the material file, the feed speed in the tool file will be used.
Parameter 7 – Options – Format: 0;0;0;0;0;0;0
This parameter provides seven options. Separate each value with a semi-colon. If the entry is left blank, all default option settings will be used. 
  1. With the first one, enter a 1 if the token is for machine code only. Enter a 2 if the token is for drawing purposes only. Enter a 0 (the default) if the token is used for both. 
  2. For the second option, enter a 1 if you want the polyline to be drawn as a region or enter a 0 (the default) if you don't (Valid for closed polylines only). 
  3. For the third option, enter a 1 if you want the first vector to be treated as a lead-in, meaning that it will be ignored for drawing purposes. Otherwise, enter 0 (the default). 
  4. For the fourth option, enter a 1 if you want the last vector to be treated as a lead-out, meaning that it will be ignored for drawing purposes. Otherwise, enter 0 (the default). 
  5. For the fifth option, enter a number that represents the sequence priority of the route. 1 is the highest priority and 99 is the lowest priority. With a value of 0 the sequence will be determined automatically. For regions, the sequence priority will be assigned to the perimeter route and the preceding sequence priority will be assigned to the pocketing route. Reserve the sequence number preceding a region and do not apply it to any other tokens. 
  6. For the sixth option enter a value that will be passed to the tool file to control the route angle. 
  7. For the seventh option enter a value that will be passed to the tool file for the angle depth for the route. A tool file must be configured to support options 6 and 7.
Parameter 8 – Tool Number & Options – Format: 102|0
The tool number for the route. If you would like to rotate the route enter a pipe symbol followed by the rotation value between 0 and 360. If a profile is desired for the route enter a pipe symbol (|) followed by the name of the profile to use.
Parameter 9 – Tool Compensation – Format: 0.125
The offset of the router bit.

Non-Associative Tokens

PLINE

 
Polyline tokens create a multi-segmented route at the specified coordinates on the specified face. 

Parameter 1- Vector Locations – Format: 30.5;0;0.25|11.578;1.127|
Enter the X, Y, and Z coordinates of each vector of the routing sequence. Each point should be separated by a semi-colon. Each group of points should be separated by a pipe (|).
The depth of the route on parts is controlled using parameter 9, which is different from the PLINE5 token that is found on parts.
Parameter 2- Bulge List – Format: 0;1;2;1;0
Enter the bulge for each vector, 0 for a straight-line route. Separate each value with a semi-colon. If the entry is left blank, all vectors will be straight.
Parameter 3- Feed Speeds – Format: 1.1;0.725;2.82
If you want to control the feed speed of the machine on a per vector basis, make a semi-colon separated list with the feed speed of each vector listed. If the entry is left blank, the feed speed in the material file will be used. If no feed is found in the material file, the feed speed in the tool file will be used.
Parameter 4- [Options] – Format: 0;0;0;0;0;0;0
This parameter provides seven options. Separate each value with a semi-colon. If the entry is left blank, all default option settings will be used.
  1. With the first option, enter a 1 if the token is for machine code only. Enter a 2 if the token is for drawing purposes only. Enter a 0 (the default) if the token is used for both.
  2. For the second option, enter a 1 if you want the polyline to be drawn as a region or enter a 0 (the default) if you don't (Valid for closed polylines only).
  3. For the third option, enter a 1 if you want the first vector to be treated as a lead-in, meaning that it will be ignored for drawing purposes. Otherwise, enter 0 (the default).
  4. For the fourth option, enter a 1 if you want the last vector to be treated as a lead-out, meaning that it will be ignored for drawing purposes. Otherwise, enter 0 (the default).
  5. For the fifth option, enter a number that represents the sequence priority of the route. 1 is the highest priority and 99 is the lowest priority. With a value of 0, the sequence will be determined automatically.
    1. For regions, the sequence priority will be assigned to the perimeter route and the preceding sequence priority will be assigned to the pocketing route. Reserve the sequence number preceding a region and do not apply it to any other tokens.
  6. For the sixth option enter a value that will be passed to the tool file to control the route angle.
  7. For the seventh option enter a value that will be passed to the tool file for the angle depth for the route. A tool file must be configured to support options 6 and 7.
Note: When a polyline machine token is added via the 2D Part Editor (or a polyline token is assigned by the Solid Model Analyzer), the default value of the first option is 3. This is a neutral value that has the same essential value as a 0. After adding a machining token has been added via the 2D Part Editor or the SMA, it is recommended to change the value from a 3 to one of the listed values (0,1,2). 
Parameter 5- Offset – Format: 21.1|19.2|5.5
This parameter can contain two groups of points that should be separated by a pipe. For the first group of points, enter an X, Y, and/or Z offset from the values in parameter 1. Each point should be separated by a semi-colon. For the second group of points enter the X center, Y center, and rotation angle. Each point should be separated by a semi-colon. All the points in parameter 1 will first be offset and then rotated about the center point by the rotation angle specified.
Parameter 6- Profile Name
If you want to assign a profile cutter to the token, enter the drawing name here.
Parameter 7- Tool Number – Format: 104
The desired tool number for the machining. 
Parameter 8- Tool Compensation – Format: 1.91
The offset of the router bit.

DXF

Load a DXF to be applied to a panel with predefined machining instructions. 

Parameter 1 –  Filename
The name of the DXF file being loaded.

GROOVE

 
Groove tokens create a straight route at the specified coordinates on the specified face using a saw. This token is listed as "Straight Line Sawing" within the Part Properties interface. 
​
Parameter 1 – Starting X Dimension
Enter the dimension for the starting point of the route in the X origin.
Parameter 2 – Starting Y Dimension
Enter the dimension for the starting point of the route in the Y origin.
Parameter 3 – Starting Z Dimension 
Enter the starting depth of the route.
Parameter 4 – Ending X Dimension
Enter the dimension for the stopping point of the route in the X origin.
Parameter 5 – Ending Y Dimension
Enter the dimension for the stopping point of the route in the Y origin.
Parameter 6 – Ending Depth/Z Dimension
Enter the ending depth of the route or leave blank if it is the same as the starting depth.
Parameter 7 – Tool Number
The number of the tool associated with this token
Parameter 8 – Tool Compensation 
The offset of the router bit or saw.
Parameter 9 – Draw Only
Set this to a value of 1 to use this token for drawing purposes only. Uncheck it if you want to use it for drawing and g-code.


ROUTE

 
Route tokens create a straight route at the specified coordinates on the specified face using a router. This token is listed as " Straight Line Routing" within the Part Properties interface. 

Parameter 1 – Starting X Dimension – Format: 18.25
Enter the dimension for the starting point of the route in the X origin.
Parameter 2 – Starting Y Dimension – Format: 16.45
Enter the dimension for the starting point of the route in the Y origin.
Parameter 3 – Starting Z Dimension – Format: 0.75
Enter the starting depth of the route.
Parameter 4 – Ending X Dimension – Format: -0.25
Enter the dimension for the stopping point of the route in the X origin.
Parameter 5 – Ending Y Dimension – Format: 0.15
Enter the dimension for the stopping point of the route in the Y origin.
Parameter 6 – Ending Depth/Z Dimension – Format: -1.4 
Enter the ending depth of the route or leave blank if it is the same as the starting depth.
Parameter 7 – Tool Number – Format: 104
The number of the tool used to create the route.
Parameter 8 – Tool Compensation – Format: 0.15
The offset of the router bit or saw.
Parameter 9 – Draw Only – Format: 1
Set this to a value of 1 to use this token for drawing purposes only. Uncheck it if you want to use it for drawing and g-code.

BORE

 
The bore token places one or more holes on the specified face of a panel. This token is listed as "Drilling Operation" within the Part Properties interface. 

Parameter 1- X Value – Format: 2.25
The distance to the centerline of the hole in X.
Parameter 2- Y Value – Format: 20.87
The distance to the centerline of the hole in Y.
Parameter 3- Z Value – Format: 0.664
The distance to the centerline of the hole in Z.
Parameter 4- Diameter (Metric) – Format: 5 
The bore diameter.
Parameter 5- End X – Format: 0.26
The dimension in X if you want an array of holes. Leave blank for one hole only.
Parameter 6- End Y – Format: 0
The dimension in Y if you want an array of holes. Leave blank for one hole only.
Parameter 7- Distance Between Holes – Format: 14.25
Enter the distance between the holes for multiple holes or leave blank if you want one hole only. Use a pipe symbol (|) to create an array of holes in both X and Y.
Parameter 8- Associative Diameter (Metric) – Format: 5
If you want this token to machine another part that has Face 5 or Face 6 touching Face 5 or Face 6 of the primary part, enter the diameter of the hole for the associated part.
Parameter 9- Associative Depth (Metric) – Format: 1.75
If you want this token to machine another part that has Face 5 or Face 6 touching Face 5 or Face 6 of the primary part, enter the depth of the hole for the associated part.

ROUTEDHOLE

 
This token makes a round cutout at a specified location in the face of the panel. It is typically used for raceways in die wall studs and grommet holes. This token is listed as "Route a Circle" within the Part Properties interface. 

Parameter 1- X Value – Format: 1.75
The dimension in X to the center of the cutout.
Parameter 2- Y Value – Format: 0.5
The dimension in Y to the center of the cutout.
Parameter 3- Z Value – Format: 0.65
The dimension in Z to the center of the cutout.
Parameter 4- Radius – Format: 12
The radius of the circle. 
Parameter 5- Route Depth – Format: 1.35
The router cut depth.
Parameter 6- Pocket – Format: 1
Enter a 1 if you want to pocket the cutout. Leave blank if you do not. You can also make a pocket by selecting a tool that has been set up for pocketing in the tool file.
Parameter 7- Tool Number – Format: 101
The desired tool number for the machining.
Parameter 8 - Draw Only – Format: 1
Select True if you want to use this token for drawing purposes only and not have G-Code produced. Select False if you want to use it for drawing and G-Code.
Parameter 9 - Sequence Number – Format: 1001
Enter a number that represents the sequence priority of the route. 1 is the highest priority and 0 (the default) is the lowest priority. This means the sequence will be determined automatically. Use the sequence numbers over 1000 to force them to come after all other routes.

CUTOUT

 
Cutout tokens make a square cutout at a specified location in the face of the panel. It is typically used for raceways in die wall studs. This token is listed as "4 Sided Cut Out" within the Part Properties interface. 

Parameter 1 - X Value – Format: 1.75
The dimension in X to the first corner of the cutout.
Parameter 2 - Y Value – Format: 1.65
The dimension in Y to the first corner of the cutout.
Parameter 3 - Route Depth – Format: 1.6
The dimension in Z to the center of the cutout.
Parameter 4 - End X – Format: 0.35
The dimension in X to the opposite corner of the cutout.
Parameter 5 - End Y – Format: 0.35
The dimension in Y to the opposite corner of the cutout.
Parameter 6 - Pocket – Format: 1
Enter a 1 if you want to pocket the cutout. Leave blank if you do not. You can also make a pocket by selecting a tool that has been set up for pocketing in the tool file.
Parameter 7 - Tool Number – Format: 102
The tool number for the machining.
Parameter 8 - Draw Only – Format: 1
Set a value of 1 to set this token to a draw only token, removing it from g-code. Leave it blank or with a value of 0 if you intend for it to appear in both drawings and g-code. 
Parameter 9 - Sequence Number – Format: 1001
Enter a number that represents the sequence priority of the route. 1 is the highest priority and 0 (the default) is the lowest priority meaning the sequence will be determined automatically. Use sequence numbers over 1000 to force them to come after all other routes.

3SIDEDNOTCH

 
3-Sided Notch tokens make a notch along the specified edge of a panel, usually for making allowance for wall cleats or raceways in cabinet sides.

Parameter 1 - X Value – Format: 1.75
The dimension in X to the first corner of the cutout.
Parameter 2 - Y Value – Format: 1.65
The dimension in Y to the first corner of the cutout.
Parameter 3 - Route Depth – Format: 1.6
The dimension in Z to the center of the cutout.
Parameter 4 - End X – Format: 0.35
The dimension in X to the opposite corner of the cutout.
Parameter 5 - End Y – Format: 0.35
The dimension in Y to the opposite corner of the cutout.
Parameter 6 - Lead-In/Lead-Out – Format: 0.75
Enter a dimension if you want a router lead-in and lead-out. Leave blank if you don’t.
Parameter 7 - Tool Number – Format: 104
The tool number for the machining.
Parameter 8 - Draw Only – Format: 1
Set a value of 1 to set this token to a draw only token, removing it from g-code. Leave it blank or with a value of 0 if you intend for it to appear in both drawings and g-code. 
Parameter 9 - Sequence Number – Format: 1
Enter a number that represents the sequence priority of the route. 1 is the highest priority and 0 (the default) is the lowest priority meaning the sequence will be determined automatically. Use sequence numbers over 1000 to force them to come after all other routes.

FILLETCORNER

 
Fillet Corner tokens round specific corners of a panel by a set radius. This token is listed as "Fillet Corner of Panel" within the Part Properties interface. 

Parameter 1 – Radius – Format: 12.125
The radius of the fillet. 
Parameter 3 – Route Depth – Format: 0.75
The depth of the router. 
Parameter 4 – Lead-In Lead-Out – Format: 0.7
Enter a dimension for a router lead-in and lead-out. This field is NOT optional.
Parameter 7 – Tool Number – Format: 104
The number of the tool associated with this token. 
Parameter 8 – Draw Only – Format: 1
Set a value of 1 to set this token to a draw only token, removing it from g-code. Leave it blank or with a value of 0 if you intend for it to appear in both drawings and g-code. 
Parameter 9 – Sequence Number – Format: 
Enter a number that represents the sequence priority of the route. 1 is the highest priority and 0 (the default) is the lowest priority meaning the sequence will be determined automatically. Use sequence numbers over 1000 to force them to come after all other routes.

RCORNERNOTCH

 
A Radius Corner Notch token makes a radiused corner notch in a specified corner of a panel.  This token is listed as "Radiused Corner Notch" within the Part Properties interface. 

Parameter 1 – Radius – Format: 12.125
The radius of the notch. 
Parameter 3 – Route Depth – Format: 0.75
The depth of the router. 
Parameter 4 – Lead-In Lead-Out – Format: 0.7
Enter a dimension for a router lead-in and lead-out. This field is NOT optional.
Parameter 7 – Tool Number – Format: 104
The number of the tool associated with this token. 
Parameter 8 – Draw Only – Format: 1
Set a value of 1 to set this token to a draw only token, removing it from g-code. Leave it blank or with a value of 0 if you intend for it to appear in both drawings and g-code. 
Parameter 9 – Sequence Number – Format: 1
Enter a number that represents the sequence priority of the route. 1 is the highest priority and 0 (the default) is the lowest priority meaning the sequence will be determined automatically. Use sequence numbers over 1000 to force them to come after all other routes.

CHAMFER

 
Chamfer tokens add a chamfer in the specified corner of the panel. This chamfer's size and angle are specified within the 1st and 2nd parameter of the token. This token is listed as "Chamfer Corner of Panel" within the Part Properties interface. 
​
Parameter 1- X Value – Format: 70
The dimension in X from the specified corner to the notch.
Parameter 2- Y Value – Format: 75
The dimension in Y from the specified corner to the notch.
Parameter 3 – Router Depth – Format: 0.5
The depth of the router in the chamfer. 
Parameter 3 – Lead-In/Lead-Out – Format: 0.75
Enter a dimension if you want a router lead-in and lead-out. Leave blank if you don’t.
Parameter 7 – Tool Number – Format: 104
The number of the tool associated with this token. 
Parameter 8 – Draw Only – Format: 1
Set a value of 1 to set this token to a draw only token, removing it from g-code. Leave it blank or with a value of 0 if you intend for it to appear in both drawings and g-code. 
Parameter 9 – Sequence Number – Format: 1100
Enter a number that represents the sequence priority of the route. 1 is the highest priority and 0 (the default) is the lowest priority meaning the sequence will be determined automatically. Use sequence numbers over 1000 to force them to come after all other routes.

CORNERNOTCH

 
Corner notch tokens make a straight notch in the specified corner of a panel. Typically, these tokens are used to create notches for the toe kick in the side of a panel. This token is listed as "Straight Corner Notch" within the Part Properties interface. 
​
Parameter 1- X Value – Format: 3
The dimension in X from the specified corner to the notch. 
Parameter 2- Y Value – Format: 76
The dimension in Y from the specified corner to the notch. 
Parameter 3 – Router Depth – Format: 19
The depth of the router. 
Parameter 4 – Lead-In Lead-Out – Format: 0.60
Enter a dimension if you want a router lead-in and lead-out. Leave blank if you don’t.
Parameter 7 – Tool Number – Format: 104
The number of the tool used to create the corner notch. 
Parameter 8 – Draw Only – Format: 1
Enter a value of 1 if you want to use this token for drawing purposes only. Leave it blank if you want to use it for drawing and g-code.
Parameter 9 – Sequence Number – Format: 0
Enter a number that represents the sequence priority of the route. 1 is the highest priority and 0 (the default) is the lowest priority meaning the sequence will be determined automatically. Use sequence numbers over 1000 to force them to come after all other routes. If pocketing is enabled, the second value separated by a comma changes the type of pocket being done.

Drawing Only Tokens

MITER

 
A Miter token makes a mitered edge along the specified edge of a panel. It is used for drawing purposes only, generating no machining code. 
​
Parameter 1 – Angle – Format: 45
The angle of the miter. 
Parameter 4 – Lead-Out – Format: 0.75 
The dimension for a lead out.
Parameter 7 – Tool Number – Format: 101 
The tool number. This is only used if the MITER token is set to the following values: '1 2' or '3 4' or '5 6' or '7 8'. These values make a cut across the part so a machine operation is added.

PROFILE

 
A Profile token makes a profiled edge along the specified edge of a panel. It is used for drawing purposes only, generating no machining code. 
​
Parameter 1 – Filename 
The file name of the drawing to extrude.  

TURNING

 
A Turning token makes a turning of a panel. It is used for drawing purposes only, generating no machining code. 
​
Parameter 1 – Filename
The file name of the drawing to use as a turning.
Parameter 2 – X Value – Format: 0
Enter the dimension for the starting point of the turning or leave blank to start at the panel origin.

MOLDING

 
A Molding token makes a molding of a panel. It is used for drawing purposes only, generating no machining code. 
​
Parameter 1 – Filename
The file name of the drawing to use as a turning.

BENDING

 
A Bending token creates a curved panel that is used for drawing purposes only, generating no machining code. 
​
Parameter 1 – Radius – Format: 20
The radius of the curved panel. A positive number will make the panel concave. A negative number will make the panel convex.
Parameter 2 – Bend Length – Format: 1
Enter a 0 or leave blank to bend the width of the panel. Enter a 1 to bend the length of the panel.
Parameter 3 – Taper Angle – Format: 8
Enter a dimension if you want the curved part to be tapered.
Parameter 4 – Tool Number – Format: 103
The tool number. This parameter only applies when a taper angle is used.

CARVING

 
A Carving token makes a carving on a panel on any one of all six faces. It is used for drawing purposes only, generating no machining code. 
​
Parameter 1 – Filename
The file name of the drawing to use as a carving.
Parameter 2 – X Value – Format: 5
Enter the dimension for the X insert point of the carving block.
Parameter 3 – Y Value – Format: 4
Enter the dimension for the Y insert point of the carving block.
Parameter 4 – Rotation Angle – Format: 180
Enter the rotation angle for the carving block or leave blank for no rotation.
Parameter 5 – Mirror X – Format: 1
Enter a 1 if you want to mirror the carving block in X. Leave blank if you don't.
Parameter 6 – Union – Format: 1
Enter a 1 if you want the carving block added to the panel. Leave blank to subtract the block from the panel.

    • Related Articles

    • Overview: Adding a New Hardware Item to the Foundation Library

      The purpose of this article is to provide an overview on the process of adding custom hardware items to your Foundation Library. The process is similar for pulls, hinges, catches, locks, latches etc. A more comprehensive tutorial on working with ...

    • Hardware from Machine Tokens (Overview)

      Microvellum software can now accumulate and populate hardware to the work order database based on specific machine tokens. It is one of the useful new Microvellum features supported in build 15.6.2201 or greater. This new ability works only with the ...

    • Hardware Machine Tokens

      The following article highlights Hardware Machine Tokens. These tokens are directly linked with the hardware itself and each token has a unique set of parameters that provide instructions for the parts. While the tokens can be customized in the User ...

    • Understanding Machine Tokens

      Understanding Machine Tokens To view the machining tokens for a part, select the part from the parts list and click on the Machining Tab under the Parts tools. All machining operations are contained in machine tokens. There are machine tokens that ...

    • Tutorial: Foundation Library Dowel & Screw Patterns

      The most recent releases of the Microvellum Foundation Library (library version 23.0609 onward) have made a few noteworthy changes to the available settings of dowels and screw patterns. This article and video were created to document those changes, ...

    • Recent Articles

    • Toolbox Release Notes | Build 25.1.1204.641

      The following release notes apply to Toolbox build 25.1.1204.641 Toolbox Login Screen Update Fig. 1: The updated Toolbox Login interface. The Toolbox Login interface has had several changes applied to it to enhance its usability and allow for greater ...

    • Toolbox Release Notes | Build 25.1.1120.641

      The following release notes apply to Toolbox build 25.1.1120.641 Mouse Wheel Fix There was a reported issue in certain interfaces (such as report groups) in which hovering over a dropdown menu (such as Output Type) would result in the options within ...

    • Dynamic Dimensioning in Toolbox BSB

      When applying dimensions to products and other solids in Toolbox BSB, by default, all dimensions are drawn in 2D on the Y plane, requiring one to switch to a top view (or an appropriately high isometric view) to see them. BricsCAD has a feature that ...

    • Toolbox Release Notes | Build 25.1.1107.641

      The following release notes apply to Toolbox build 25.1.1107.641. Subassembly Prompt Fixes A pair of issues were reportedly occurring when attempting to work with subassembly prompts in the Edit Design Data interface. Subassemblies copied to the ...

    • Microvellum Foundation Library Release Notes | Build 25.1024

      The following release notes apply to the Microvellum Foundation Library build 25.1024. Additions Added Face Profile Options to the Door Wizard for enhanced design flexibility. Users can now apply decorative visual profiles to doors, drawer fronts, ...